Category
Send your part number — quotes typically within hours.
WhatsAppMon–Sat · 9:00–18:00 GMT+8
Why Hooguu Tools
- 📦250,000+ SKUs in stock
- 🏷️50+ brands, all genuine OEM
- ✈️Worldwide via DHL/FedEx
- ↩️30-day money-back
Reaming is the least glamorous operation in the shop and the one most often done badly. A reamer removes only 0.1–0.5 mm of diameter, yet it is expected to deliver an IT7 hole, a 0.8 µm Ra surface and a roundness figure that a boring bar struggles to match at the same cycle time. Because the stock allowance is so small, everything upstream of the reamer — pre-hole diameter, runout, coolant, holder choice — accounts for most of the result. The reamer itself only has to be geometrically correct, rigid and fed at the right rate.
This guide compares two of the most widely specified solid carbide reaming platforms in general subcontract machining: the Sandvik CoroReamer 435 and the Iscar Bayo T-Ream replaceable-head system. Both are aimed at the same 8–20 mm H7 hole in steel, and both are usually run on the same machining centre. The differences are in architecture, in how the tool is renewed when it wears, and in the cutting data window each design tolerates.
Why reaming still beats boring on cycle time
A reamer cuts with many flutes simultaneously, so the radial force per flute is low and the tool self-centres in the pre-hole. That is why a 6-flute reamer can hold a 0.02 mm diameter band at a feed of 0.5 mm/rev, while a single-point boring bar at the same diameter needs a spring pass and a much slower feed to reach a comparable surface finish.
The trade-off is that a reamer follows the pre-hole. It corrects diameter, roundness and surface finish, but it does not correct position, straightness or angular error. If the hole is 0.05 mm off-centre after drilling, it will still be 0.05 mm off-centre after reaming. For position-critical work, drill–bore–ream is the correct sequence; for diameter and finish, drill–ream is enough.
| Process | Typical IT grade | Typical Ra (µm) | Corrects position error? | Cycle time at Ø12 mm |
|---|---|---|---|---|
| Twist drilling | IT11–IT13 | 3.2–12.5 | — | Baseline |
| Drill + ream | IT7–IT8 | 0.4–1.6 | No | Baseline + 15–25% |
| Drill + bore + ream | IT6–IT7 | 0.4–0.8 | Yes (at boring stage) | Baseline + 60–90% |
| Fine boring only | IT6–IT7 | 0.8–1.6 | Yes | Baseline + 40–70% |
| Drill + ball burnish | IT7–IT8 | 0.1–0.4 | No | Baseline + 20–35% |
Platform architecture: solid carbide versus replaceable head
The CoroReamer 435 is a one-piece solid carbide reamer. Carbide from shank to tip means maximum static stiffness and the shortest possible force path into the holder, which is the reason this type of tool dominates holes below 12 mm where a steel shank would be proportionally too flexible. When the cutting edge wears, the tool is reground and re-coated, and the diameter is brought back to nominal by the regrinding service.
The Bayo T-Ream takes the opposite approach: a short solid carbide cutting head is mounted on a hardened steel shank with a self-clamping interface. The head carries the flutes, the chamfer and the coolant outlets; the shank carries the length and the holder interface. When the head wears, it is replaced and the shank stays in the machine. The practical consequence is that the effective diameter range of one shank is covered by a family of heads, and a worn head can be swapped in seconds without touching the tool offset library in a way that requires re-measuring the whole assembly length.
| Characteristic | Sandvik CoroReamer 435 | Iscar Bayo T-Ream |
|---|---|---|
| Construction | One-piece solid carbide | Carbide head on steel shank |
| Typical diameter range | Approx. 4–20 mm | Approx. 8–32 mm with head family |
| Flute count | 4 flutes in the common sizes, helical | 4–6 flutes depending on diameter |
| Standard tolerance | H7 as standard, other classes on request | H7 head, fine increments across the range |
| Coolant | Internal through-flute | Internal through-flute |
| Entry chamfer | 45° lead chamfer as standard | 45° lead chamfer, guided entry |
| Renewal method | Regrind and re-coat | Head replacement |
| Stiffness in small diameters | Best (no joint) | Joint adds compliance below 8 mm |
| Best fit | High-volume fixed sizes, small holes | Mixed-size families, large holes, unattended cells |
Flute geometry and what it does to the hole
Flute count is the single most consequential geometric choice on a reamer. More flutes mean more simultaneous cutting edges, which improves roundness and reduces the load per edge, but it also reduces chip space. A 6-flute reamer in a 10 mm hole has roughly half the chip gullet area of a 4-flute tool at the same diameter, and reaming produces a continuous, tightly curled chip that has to leave the hole without packing. Packed chips are the number one cause of oversize holes and torn surfaces.
- 4 flutes: the safe default for 4–12 mm in ductile steels and stainless, where chip evacuation matters more than roundness. Larger gullets tolerate interrupted coolant and horizontal holes.
- 6 flutes: the standard for 12–20 mm in steel and cast iron, where the pre-hole is well controlled and the priority is roundness and surface finish. Requires reliable through-tool coolant.
- Helical flutes: a right-hand helix pulls the chip ahead of the tool in a through hole, which is desirable, but in a blind hole it pushes the chip to the bottom. For blind holes, a straight-flute or slow-helix reamer with strong internal coolant is the safer choice.
The lead chamfer matters more than most programmers expect. A 45° chamfer with a short land guides the tool into the pre-hole and progressively engages the flutes; a chamfer that is too long or too sharp will chatter on entry and bell-mouth the first 2–3 mm of the hole. If a hole is consistently oversized at the entrance only, the chamfer geometry and the entry feed are the first two things to check, not the reamer diameter.
Pre-hole preparation: the allowance table
Reaming allowance is diametric stock left by the previous operation. Too little and the reamer rubs, work-hardens the surface and wears on the margin instead of the cutting edge. Too much and the flutes overload, the chip packs and the hole goes oversize. The table below is a practical starting point for ductile steels and cast irons; add 0.05 mm for stainless and nickel alloys, and subtract 0.05 mm for aluminium.
| Nominal diameter (mm) | Diametric allowance (mm) | Pre-hole tolerance | Pre-hole Ra target |
|---|---|---|---|
| 3–6 | 0.10–0.20 | ±0.03 | ≤ 3.2 µm |
| 6–10 | 0.15–0.30 | ±0.04 | ≤ 3.2 µm |
| 10–18 | 0.20–0.40 | ±0.05 | ≤ 6.3 µm |
| 18–30 | 0.30–0.50 | ±0.06 | ≤ 6.3 µm |
| 30–50 | 0.40–0.70 | ±0.08 | ≤ 6.3 µm |
Note that the pre-hole must be round. A drill that has produced a three-lobed hole from an unbalanced point geometry will transfer that lobing through the reamer, because the reamer is guided by the existing surface. If roundness is the requirement, the pre-hole needs either a spot-and-drill sequence with a properly ground point, or a short boring pass.
Cutting data: speeds and feeds that actually hold H7
Reaming is a low-speed, high-feed operation. The cutting speed is deliberately kept low to avoid built-up edge and thermal growth of the tool, and the feed per revolution is high because each flute only takes a thin chip. The two platforms respond differently: the solid carbide 435 tolerates the upper half of the speed window better, because there is no joint to deflect, while the Bayo head prefers the middle of the window with a slightly higher feed to keep the edge loaded.
| Material | Vc (m/min) | Feed (mm/rev) | Coolant pressure | Notes |
|---|---|---|---|---|
| Low carbon steel (C22, 1018) | 18–28 | 0.40–0.70 | 10–20 bar | Watch built-up edge at low Vc |
| Alloy steel (42CrMo4, 4140) | 12–22 | 0.35–0.60 | 15–25 bar | Most common H7 application |
| Case hardening steel (16MnCr5) | 15–25 | 0.35–0.60 | 15–25 bar | Ream before hardening |
| Stainless 304 / 316L | 6–12 | 0.25–0.50 | 20–35 bar | Sharp edge, no margin rubbing |
| Duplex / 17-4PH | 5–10 | 0.20–0.40 | 25–40 bar | Generous allowance, avoid dwell |
| Grey cast iron GJL-250 | 15–25 | 0.50–0.90 | 8–15 bar | Dry or MQL possible in through holes |
| Ductile iron GJS-600 | 12–20 | 0.45–0.80 | 10–20 bar | Dust and fines need flushing |
| Aluminium 6061 / 7075 | 40–80 | 0.50–1.00 | 10–20 bar | High helix, polished flutes |
| Titanium Ti-6Al-4V | 4–9 | 0.15–0.30 | 30–50 bar | Never dwell, keep edge engaged |
| Inconel 718 | 3–6 | 0.10–0.25 | 40–70 bar | Consider boring instead |
Speeds above roughly 30 m/min in steel are counter-productive: the tool grows thermally during the pass, the last millimetres of the hole come out oversize, and the surface shows a characteristic smeared appearance. If the machine has no coolant-through capability, cut the upper speed figure by 20% and reduce feed by 10% to compensate for poorer chip evacuation.
Runout and holder selection
An H7 reamer has roughly 0.018 mm of diameter tolerance at Ø12 mm. A holder with 0.03 mm runout consumes the entire tolerance before the tool even starts cutting, and the result is a hole that is simultaneously oversize on one side and undersize on the other. Runout targets for reaming are strict:
| Holder type | Typical TIR | Suitable for reaming? | Comment |
|---|---|---|---|
| Hydraulic expansion chuck | 0.003–0.010 mm | Excellent | Best balance of accuracy and damping |
| Shrink-fit chuck | 0.003–0.008 mm | Excellent | Highest stiffness, needs a shrink unit |
| Precision collet (up to 0.005 mm class) | 0.005–0.015 mm | Good | Collet and nut must be clean and matched |
| Standard ER collet | 0.015–0.030 mm | Marginal | Only with fresh collets and light cuts |
| Drill chuck / side-lock | 0.03–0.10 mm | No | Guarantees an out-of-tolerance hole |
Also check spindle taper condition and the machine’s thermal state. A machine that has been idle overnight will produce a different hole diameter for the first 20 minutes of running than it will after two hours of production. For tight-limit work, warm up the spindle and run a first-off part that is measured and scrapped deliberately.
Coolant strategy
Reaming produces a long, continuous chip from a nearly closed cutting zone, so coolant is doing two jobs: cooling the margin and flushing the chip. Internal through-flute coolant directed at the cutting zone is the only reliable method for holes deeper than about 1.5×D. Flood coolant from outside reaches the entrance chamfer and little else.
- Through holes, steel: 10–20 bar through-tool, 6–8% emulsion. The chip exits ahead of the tool.
- Blind holes: 20–40 bar and a reduced penetration rate on entry so the chip is flushed before the flutes fill. A dwell at the bottom is fatal — it burnishes the floor and work-hardens the corner.
- Stainless and nickel alloys: 25–50 bar, higher concentration emulsion or neat oil for the most difficult grades. Sulphur-free extreme pressure additives help with 17-4PH and duplex.
- Cast iron: dry or minimum quantity lubrication is viable in through holes because the chip is friable, but blind holes still need air/oil mist to clear fines.
Troubleshooting: reading the hole
| Symptom | Most likely cause | Corrective action |
|---|---|---|
| Hole uniformly oversize | Reamer diameter, thermal growth, or runout | Measure at 20 °C, check TIR, reduce Vc by 20% |
| Oversize only at entry | Long or sharp chamfer, high entry feed | Shorten chamfer, reduce feed for first 2 mm |
| Tapered hole | Misalignment between spindle and pre-hole | Use a floating holder, check pre-hole straightness |
| Bell-mouthed entry | Chatter on entry, unstable setup | Rigid holder, lower speed, increase feed slightly |
| Poor Ra with correct diameter | Built-up edge or margin rubbing | Increase Vc out of the BUE range, sharpen/replace |
| Lobed / out-of-round hole | Multi-lobe pre-hole, insufficient flutes | Improve drill point, add a boring pass |
| Chip packing, torn surface | Too many flutes for the chip volume, low pressure | Fewer flutes, raise coolant pressure, reduce feed |
| Rapid flank wear on one flute | Runout or eccentric pre-hole | Re-seat tool, check holder and spindle taper |
Worked example: Ø12 H7 in 42CrMo4
A hydraulic cylinder block in 42CrMo4 (roughly 280 HB) needs a Ø12 H7 (+0.018/0) hole, 36 mm deep, 400 pieces per batch. The pre-hole is drilled at Ø11.60 mm, leaving 0.40 mm diametric allowance — at the upper end of the 10–18 mm band, which is appropriate for a ductile alloy steel where a slightly heavier cut keeps the edge loaded rather than rubbing.
- Speed: Vc = 16 m/min → n = 1000 × 16 / (π × 12) ≈ 424 rpm
- Feed: f = 0.45 mm/rev → vf ≈ 191 mm/min
- Cycle time: 36 mm cut + 3 mm approach at 191 mm/min ≈ 0.20 min per hole
- Coolant: 20 bar through-tool, 7% emulsion
- Holder: hydraulic chuck, TIR verified ≤ 0.01 mm before the batch
- Expected result: Ø12.008–12.014 mm, roundness within 0.005 mm, Ra 0.6–1.0 µm
At these values the reamer is doing very little work per hole — the chip is thin and the thermal load is low — which is exactly the condition under which both platforms hold tolerance for a long time. The failure mode to watch in a 400-piece batch is not sudden breakage but gradual diameter drift as the margin wears. Measure the first five holes, then every twentieth, and plot the diameter; a drift of more than 0.004 mm over 50 holes means the tool is rubbing rather than cutting and the feed should be raised slightly.
Which platform fits which shop
Choose the solid carbide CoroReamer 435 when the hole sizes are fixed and repeatable, when diameters are below 12 mm, and when the machine has reliable through-tool coolant. The absence of a joint gives the best stiffness per euro of tooling and the most predictable diameter behaviour in small holes. Regrinding cycles are well understood, and a shop with a regrinding supplier can keep a family of sizes running indefinitely.
Choose the Bayo T-Ream when the shop runs a wide spread of hole sizes on the same machine, when heads need to be changed at the machine without re-measuring the whole assembly, or when the cell runs unattended and a worn head must be replaced by an operator with minimal intervention. The replaceable head also removes the regrinding logistics entirely — there is no queue, no diameter compensation after regrinding, and no risk of a reground tool drifting outside its tolerance band.
Neither platform compensates for a poorly prepared pre-hole. In practice, the shops that get consistent IT7 results from either tool are the ones that control the drilling operation, verify holder runout before every batch, and measure holes with a bore gauge at a stable temperature. The reamer is the last 0.3 mm of a process that was decided several operations earlier.
Selection checklist
- Confirm the required IT grade: reaming reaches IT7–IT8 reliably; IT6 usually needs a boring pass.
- Set the diametric allowance from the table above and hold the pre-hole diameter within ±0.05 mm.
- Match flute count to chip volume, not to the catalogue default: fewer flutes for gummy stainless, more for stable steel and cast iron.
- Verify holder TIR ≤ 0.01 mm and warm up the spindle before the first-off part.
- Use internal coolant at 10–20 bar minimum, and never dwell at the bottom of a blind hole.
- Keep Vc in the 12–22 m/min band for alloy steel; higher speeds buy nothing and cost diameter control.
- Trend the hole diameter across the batch rather than inspecting only the first part.
Reaming rewards discipline rather than tooling sophistication. A correctly prepared pre-hole, a rigid holder and a conservative speed will produce H7 holes from either of these platforms; a careless pre-hole will defeat both.
Shop Related Products at HOOGUU
Written by wg
Need Help?
Can't find a part number, need bulk pricing, or want a custom quote?
Currency
Show prices in your local currency.
Shop by Brand
View all 50+ brands →CNC Knowledge Hub
- Sandvik CoroReamer 435 vs Iscar Bayo T-Ream: Solid Carbide Reaming Com… Nov 18, 2026
- ZCC.CT YBC Turning Grades Explained: YBC151, YBC251 and YBC351 Coating… Nov 17, 2026
- Titanium Milling Tool Selection Guide: Insert Grades, Geometry and Cut… Nov 17, 2026
- Brass, Bronze and Copper Machining Best Practices: Cutting Parameters,… Nov 16, 2026