Category
Send your part number — quotes typically within hours.
WhatsAppMon–Sat · 9:00–18:00 GMT+8
Why Hooguu Tools
- 📦250,000+ SKUs in stock
- 🏷️50+ brands, all genuine OEM
- ✈️Worldwide via DHL/FedEx
- ↩️30-day money-back
Every CNC programmer and machinist eventually hits the same wall: a cut that looks correct on paper produces a spindle alarm, stalls the servos, or leaves a finish that looks like it was made with a hacksaw. In most cases the root cause is not the tool, the material, or the program — it is an uncalculated specific cutting force that exceeds the available spindle power. This reference collects the specific cutting force (kc) values, chip-thinning correction factors, and the exact formulas used to predict spindle power and torque for turning, milling, and drilling. Use it as a shop-floor companion before you push a cycle start button.
1. What Is Specific Cutting Force (kc)?
Specific cutting force, denoted kc and expressed in N/mm², is the cutting force required to remove one square millimetre of chip cross-section. It is a material property that depends on the workpiece strength, the cutting speed, the rake angle, and the chip thickness. The reference value, kc1.1, is measured at a standardized chip thickness of h = 1.1 mm and a rake angle of γ = 0°.
The active specific cutting force for any other chip thickness is corrected with the well-known Kienzle formula:
kc = kc1.1 × (1.1 / h)mc
where mc is the chip-thickness exponent (typically 0.10–0.22) and h is the equivalent chip thickness in mm. This formula explains why light finishing cuts need proportionally more power per cubic centimetre removed than heavy roughing passes: thinner chips are harder to shear, so kc rises.
Reference kc1.1 Values by Material
| Material | Grade | Tensile Rm (MPa) | kc1.1 (N/mm²) | mc |
|---|---|---|---|---|
| Unalloyed steel | Ck45 / AISI 1045 | 600–700 | 2,100 | 0.14 |
| Alloy steel | 42CrMo4 / 4140 | 900–1100 | 2,350 | 0.13 |
| Hardened steel | 1.7225 (45 HRC) | 1500–1800 | 2,900 | 0.12 |
| Stainless austenitic | AISI 304 / 1.4301 | 500–700 | 2,450 | 0.17 |
| Stainless austenitic | AISI 316L / 1.4404 | 480–620 | 2,500 | 0.18 |
| Stainless martensitic | 1.4021 / X20Cr13 | 650–850 | 2,550 | 0.15 |
| Duplex stainless | 1.4462 | 700–900 | 2,700 | 0.16 |
| Grey cast iron | GJL-250 / ASTM A48 35 | 250 HB | 1,450 | 0.12 |
| Spheroidal cast iron | GJS-600-3 | 600 MPa | 1,750 | 0.13 |
| Compacted graphite iron | CGI | 450 MPa | 1,900 | 0.14 |
| Aluminium alloy | AlSi1MgMn / 6082 | 250–310 | 750 | 0.18 |
| Aluminium casting | AlSi7Mg / A356 | 200–250 | 700 | 0.20 |
| Copper alloy | CuZn39Pb3 / 360 | 350–450 | 1,250 | 0.15 |
| Bronze | CuSn12Ni2 | 300–400 | 1,150 | 0.16 |
| Titanium | Ti-6Al-4V | 900–1100 | 2,300 | 0.20 |
| Titanium | Ti-5553 | 1100–1300 | 2,500 | 0.19 |
| Nickel alloy | Inconel 718 (aged) | 1250–1400 | 3,500 | 0.15 |
| Nickel alloy | Inconel 625 | 760–900 | 3,100 | 0.16 |
| Hardened tool steel | H13 (52 HRC) | >1800 | 3,200 | 0.12 |
| Compacted / sintered | PM steel | 700–1000 | 2,200 | 0.14 |
Values are representative for carbide tools with dry or emulsion cooling at moderate Vc. For PCD on aluminium subtract 10–15%.
2. Equivalent Chip Thickness (h) for Each Operation
Before applying Kienzle, you must convert your feed into an equivalent chip thickness h:
| Operation | Chip cross-section A (mm²) | Equivalent chip thickness h (mm) |
|---|---|---|
| Turning (straight) | ap × f | f × sin(κr) |
| Turning (round insert) | ap × f | h = f (use feed directly if κr ≈ 90°) |
| Face milling | ap × ae × fz × Z / (π × D) | h = fz × sin(κr) × (π × ae / (D × Z)) … approx |
| End / shoulder milling | ap × fz | h = fz × sin(κr) |
| High-feed milling | ap × fz | h = fz × sin(κr) (chip-thinning factor up to 0.45 for κr=17°) |
| Drilling | (π × D²) / 4 × f | h = f × sin(κr) ≈ f × 0.7 (chisel edge) |
For practical power estimation it is often sufficient to use the nominal feed as h, then bump kc by 10–20% for safety.
3. Power Calculation Formulas
Net cutting power Pc at the tool is the product of the tangential cutting force Fc and the cutting speed Vc. Divide by the machine efficiency η (0.70–0.85 for belt-driven spindles, 0.85–0.95 for direct-drive) to obtain the required spindle power Pspindle at the motor.
| Operation | Material removal rate Q (cm³/min) | Net power Pc (kW) |
|---|---|---|
| Turning | ap × f × Vc | kc × ap × f × Vc / 60,000 |
| Milling | ap × ae × vf / 1,000 | kc × ap × ae × vf / 60,000 |
| Drilling | (π × D² / 4) × f × n / 1,000 | kc × (π × D² / 4) × f × n / 60,000 |
Units: ap, ae, f in mm; Vc in m/min; vf in mm/min; D in mm; n in rpm; kc in N/mm².
The generic form, easy to remember, is:
Pc (kW) = kc (N/mm²) × Q (cm³/min) / 60,000
And the torque T at the spindle in Nm:
T (Nm) = 9,550 × Pc (kW) / n (rpm)
4. Power Requirement Tables by Operation
The tables below give the net cutting power Pc in kW for representative depths and feeds at the indicated Vc. Add 15–30% for the drive train before comparing with the spindle’s rated power.
Turning Power (Pc in kW)
| Material | ap (mm) | f (mm/rev) | Vc (m/min) | Q (cm³/min) | kc (N/mm²) | Pc (kW) |
|---|---|---|---|---|---|---|
| Ck45 steel | 3.0 | 0.30 | 250 | 225 | 2,300 | 8.6 |
| 42CrMo4 | 2.5 | 0.25 | 180 | 112.5 | 2,600 | 4.9 |
| AISI 316L | 2.0 | 0.20 | 120 | 48 | 2,850 | 2.3 |
| GJL-250 cast iron | 4.0 | 0.40 | 300 | 480 | 1,500 | 12.0 |
| AlSi7Mg aluminium | 5.0 | 0.50 | 800 | 2,000 | 780 | 26.0 |
| Ti-6Al-4V titanium | 1.5 | 0.18 | 60 | 16.2 | 2,900 | 0.78 |
| Inconel 718 | 1.0 | 0.15 | 40 | 6.0 | 3,900 | 0.39 |
Face / Shoulder Milling Power (Pc in kW)
| Material | ap (mm) | ae (mm) | vf (mm/min) | Q (cm³/min) | kc | Pc (kW) |
|---|---|---|---|---|---|---|
| Ck45 steel | 5.0 | 50 | 2,400 | 600 | 2,300 | 23.0 |
| 42CrMo4 | 4.0 | 40 | 1,600 | 256 | 2,600 | 11.1 |
| AISI 304 | 3.0 | 30 | 1,200 | 108 | 2,700 | 4.9 |
| GJL-250 | 6.0 | 80 | 3,200 | 1,536 | 1,500 | 38.4 |
| Aluminium 6082 | 8.0 | 60 | 8,000 | 3,840 | 750 | 48.0 |
| Ti-6Al-4V | 3.0 | 20 | 600 | 36 | 2,900 | 1.74 |
| Inconel 718 | 2.0 | 20 | 400 | 16 | 3,900 | 1.04 |
Drilling Power (Pc in kW) — Solid Carbide, κr=140°
| Material | D (mm) | f (mm/rev) | n (rpm) | Q (cm³/min) | kc | Pc (kW) |
|---|---|---|---|---|---|---|
| Ck45 | 10 | 0.18 | 6,370 | 90.0 | 2,600 | 3.9 |
| 42CrMo4 | 12 | 0.16 | 4,240 | 76.8 | 2,900 | 3.7 |
| 316L | 8 | 0.10 | 3,980 | 20.0 | 3,200 | 1.07 |
| GJL-250 | 14 | 0.25 | 6,820 | 262 | 1,600 | 7.0 |
| Aluminium 6082 | 10 | 0.30 | 19,100 | 450 | 820 | 6.15 |
5. Worked Examples
Example 1 — Turning 42CrMo4 at ap=2.5, f=0.25, Vc=180
- Q = 2.5 × 0.25 × 180 = 112.5 cm³/min
- h = f = 0.25 mm; kc = 2,350 × (1.1/0.25)0.13 = 2,350 × 1.20 = 2,820 N/mm²
- Pc = 2,820 × 112.5 / 60,000 = 5.29 kW (net)
- With η = 0.80: Pspindle = 5.29 / 0.80 = 6.6 kW
- n = 1,000 × 180 / (π × 80) = 716 rpm; T = 9,550 × 5.29 / 716 = 70.5 Nm
Example 2 — Face milling Ck45 with a ø63 face mill, Z=5, ap=5, ae=50, Vc=200, fz=0.15
- n = 1,000 × 200 / (π × 63) = 1,010 rpm
- vf = 0.15 × 5 × 1,010 = 758 mm/min
- Q = 5 × 50 × 758 / 1,000 = 189.5 cm³/min
- Pc = 2,300 × 189.5 / 60,000 = 7.26 kW (net) → ~9.1 kW at spindle
Example 3 — Drilling GJL-250 with ø14 carbide drill, f=0.25, Vc=300
- n = 1,000 × 300 / (π × 14) = 6,820 rpm
- Q = (π × 14² / 4) × 0.25 × 6,820 / 1,000 = 262 cm³/min
- Pc = 1,600 × 262 / 60,000 = 6.99 kW (net) → ~8.7 kW at spindle
6. Torque vs. Speed: Respecting the Spindle Limit Curve
CNC spindles deliver constant torque up to a corner speed (typically 1,000–3,000 rpm) and constant power above it. A cut that is fine at 6,000 rpm can stall the spindle at 1,200 rpm because torque demand rises as n drops. The rule of thumb:
- Below the corner speed, check torque T = 9,550 × Pc / n against the rated torque.
- Above the corner speed, check power Pspindle against the rated power.
- For heavy roughing of steel at low rpm, torque is usually the binding constraint; for high-speed aluminium milling, power is.
7. Brand-Specific Cutting Data Reference
Catalogue data from the major toolmakers align closely with the kc model when Vc, fz and ap are converted back to Q. The table below summarizes recommended removal rates for a 15 kW (S6-40%) spindle under continuous cut, with carbide inserts.
| Material | Sandvik (GC4325 / CoroMill 490) | Iscar (IC8250 / HELIDO) | Seco (TP3501 / Turbo 12) |
|---|---|---|---|
| Steel P20-35 | Vc 200, fz 0.15, ap 5 | Vc 180, fz 0.16, ap 5 | Vc 210, fz 0.14, ap 4.5 |
| Stainless M20-30 | Vc 130, fz 0.12, ap 3 | Vc 120, fz 0.13, ap 3 | Vc 140, fz 0.11, ap 3 |
| Cast iron K20-30 | Vc 300, fz 0.20, ap 6 | Vc 280, fz 0.22, ap 6 | Vc 320, fz 0.18, ap 5.5 |
| Aluminium N | Vc 800, fz 0.25, ap 8 | Vc 900, fz 0.28, ap 8 | Vc 850, fz 0.26, ap 8 |
| Titanium S | Vc 70, fz 0.10, ap 2 | Vc 60, fz 0.12, ap 2 | Vc 75, fz 0.09, ap 2 |
All three vendors converge on the same power envelope because the physics is material-driven; the differences are 5–15% and reflect coating, edge preparation, and insert geometry. Always derate by at least 20% for interrupted cuts and 15% for long overhangs.
8. Practical Guidelines
- Stay below 80% of rated power for continuous cuts. The last 20% is your safety margin for worn tools, hard spots, and coolant drop-out.
- Reduce ap, not f, when power is tight. Cutting force scales linearly with ap but feed also affects surface finish and chip control; prefer splitting a heavy pass into two lighter passes.
- Use high-pressure coolant (70+ bar) for stainless, titanium, and superalloys. It can reduce effective kc by 5–10% and dramatically extend tool life at the same Vc.
- Chip thinning in high-feed and circular milling means h is much smaller than fz; your effective kc goes up, not down. Increase fz proportionally to restore the target h and keep the cut economical.
- Drill power spikes at entry and exit. The chisel edge of a twist drill can double the peak kc; use a spot drill or chamfer to reduce the entry shock.
- Monitor spindle load meter. A sustained reading above 85% in steady state means the cut is too heavy; above 95% and an immediate pull-back is warranted.
9. Conclusion
Specific cutting force kc is the single number that connects workpiece material, chip cross-section, and machine capacity. By calculating Q from your depths and feeds, looking up kc1.1 for the material, and applying the Kienzle correction for chip thickness, you can predict spindle power and torque before the tool touches the part. The worked examples and the Sandvik/Iscar/Seco reference table give you the anchor points; the rule of staying under 80% of rated power gives you the margin. A 60-second power check before cycle start is the cheapest insurance in the workshop.
Shop Related Products at HOOGUU
Written by wg
Need Help?
Can't find a part number, need bulk pricing, or want a custom quote?
Currency
Show prices in your local currency.
Shop by Brand
View all 50+ brands →CNC Knowledge Hub
- Specific Cutting Force (kc) and Spindle Power Calculation Reference: T… Nov 15, 2026
- Iscar IC908, IC808 and IC5100 PVD Turning Grades Explained: Coating Te… Nov 15, 2026
- CoroMill 210 and FEEDMILL High-Feed Milling Best Practices: Chip Thinn… Nov 14, 2026
- Kyocera vs Korloy Cast Iron Turning Grades Compared: CA5525, CA6525, C… Nov 14, 2026