🚚 Free Worldwide Shipping · 🛃 Free Customs Clearance · ⏱️ Delivery in 15–30 Days

Authorised CNC Cutting Tool Supplier · Direct from China

Specific Cutting Force (kc) and Spindle Power Calculation Reference: Tables for Turning, Milling and Drilling

Every CNC programmer and machinist eventually hits the same wall: a cut that looks correct on paper produces a spindle alarm, stalls the servos, or leaves a finish that looks like it was made with a hacksaw. In most cases the root cause is not the tool, the material, or the program — it is an uncalculated specific cutting force that exceeds the available spindle power. This reference collects the specific cutting force (kc) values, chip-thinning correction factors, and the exact formulas used to predict spindle power and torque for turning, milling, and drilling. Use it as a shop-floor companion before you push a cycle start button.

1. What Is Specific Cutting Force (kc)?

Specific cutting force, denoted kc and expressed in N/mm², is the cutting force required to remove one square millimetre of chip cross-section. It is a material property that depends on the workpiece strength, the cutting speed, the rake angle, and the chip thickness. The reference value, kc1.1, is measured at a standardized chip thickness of h = 1.1 mm and a rake angle of γ = 0°.

The active specific cutting force for any other chip thickness is corrected with the well-known Kienzle formula:

kc = kc1.1 × (1.1 / h)mc

where mc is the chip-thickness exponent (typically 0.10–0.22) and h is the equivalent chip thickness in mm. This formula explains why light finishing cuts need proportionally more power per cubic centimetre removed than heavy roughing passes: thinner chips are harder to shear, so kc rises.

Reference kc1.1 Values by Material

Material Grade Tensile Rm (MPa) kc1.1 (N/mm²) mc
Unalloyed steel Ck45 / AISI 1045 600–700 2,100 0.14
Alloy steel 42CrMo4 / 4140 900–1100 2,350 0.13
Hardened steel 1.7225 (45 HRC) 1500–1800 2,900 0.12
Stainless austenitic AISI 304 / 1.4301 500–700 2,450 0.17
Stainless austenitic AISI 316L / 1.4404 480–620 2,500 0.18
Stainless martensitic 1.4021 / X20Cr13 650–850 2,550 0.15
Duplex stainless 1.4462 700–900 2,700 0.16
Grey cast iron GJL-250 / ASTM A48 35 250 HB 1,450 0.12
Spheroidal cast iron GJS-600-3 600 MPa 1,750 0.13
Compacted graphite iron CGI 450 MPa 1,900 0.14
Aluminium alloy AlSi1MgMn / 6082 250–310 750 0.18
Aluminium casting AlSi7Mg / A356 200–250 700 0.20
Copper alloy CuZn39Pb3 / 360 350–450 1,250 0.15
Bronze CuSn12Ni2 300–400 1,150 0.16
Titanium Ti-6Al-4V 900–1100 2,300 0.20
Titanium Ti-5553 1100–1300 2,500 0.19
Nickel alloy Inconel 718 (aged) 1250–1400 3,500 0.15
Nickel alloy Inconel 625 760–900 3,100 0.16
Hardened tool steel H13 (52 HRC) >1800 3,200 0.12
Compacted / sintered PM steel 700–1000 2,200 0.14

Values are representative for carbide tools with dry or emulsion cooling at moderate Vc. For PCD on aluminium subtract 10–15%.

2. Equivalent Chip Thickness (h) for Each Operation

Before applying Kienzle, you must convert your feed into an equivalent chip thickness h:

Operation Chip cross-section A (mm²) Equivalent chip thickness h (mm)
Turning (straight) ap × f f × sin(κr)
Turning (round insert) ap × f h = f (use feed directly if κr ≈ 90°)
Face milling ap × ae × fz × Z / (π × D) h = fz × sin(κr) × (π × ae / (D × Z)) … approx
End / shoulder milling ap × fz h = fz × sin(κr)
High-feed milling ap × fz h = fz × sin(κr) (chip-thinning factor up to 0.45 for κr=17°)
Drilling (π × D²) / 4 × f h = f × sin(κr) ≈ f × 0.7 (chisel edge)

For practical power estimation it is often sufficient to use the nominal feed as h, then bump kc by 10–20% for safety.

3. Power Calculation Formulas

Net cutting power Pc at the tool is the product of the tangential cutting force Fc and the cutting speed Vc. Divide by the machine efficiency η (0.70–0.85 for belt-driven spindles, 0.85–0.95 for direct-drive) to obtain the required spindle power Pspindle at the motor.

Operation Material removal rate Q (cm³/min) Net power Pc (kW)
Turning ap × f × Vc kc × ap × f × Vc / 60,000
Milling ap × ae × vf / 1,000 kc × ap × ae × vf / 60,000
Drilling (π × D² / 4) × f × n / 1,000 kc × (π × D² / 4) × f × n / 60,000

Units: ap, ae, f in mm; Vc in m/min; vf in mm/min; D in mm; n in rpm; kc in N/mm².

The generic form, easy to remember, is:

Pc (kW) = kc (N/mm²) × Q (cm³/min) / 60,000

And the torque T at the spindle in Nm:

T (Nm) = 9,550 × Pc (kW) / n (rpm)

4. Power Requirement Tables by Operation

The tables below give the net cutting power Pc in kW for representative depths and feeds at the indicated Vc. Add 15–30% for the drive train before comparing with the spindle’s rated power.

Turning Power (Pc in kW)

Material ap (mm) f (mm/rev) Vc (m/min) Q (cm³/min) kc (N/mm²) Pc (kW)
Ck45 steel 3.0 0.30 250 225 2,300 8.6
42CrMo4 2.5 0.25 180 112.5 2,600 4.9
AISI 316L 2.0 0.20 120 48 2,850 2.3
GJL-250 cast iron 4.0 0.40 300 480 1,500 12.0
AlSi7Mg aluminium 5.0 0.50 800 2,000 780 26.0
Ti-6Al-4V titanium 1.5 0.18 60 16.2 2,900 0.78
Inconel 718 1.0 0.15 40 6.0 3,900 0.39

Face / Shoulder Milling Power (Pc in kW)

Material ap (mm) ae (mm) vf (mm/min) Q (cm³/min) kc Pc (kW)
Ck45 steel 5.0 50 2,400 600 2,300 23.0
42CrMo4 4.0 40 1,600 256 2,600 11.1
AISI 304 3.0 30 1,200 108 2,700 4.9
GJL-250 6.0 80 3,200 1,536 1,500 38.4
Aluminium 6082 8.0 60 8,000 3,840 750 48.0
Ti-6Al-4V 3.0 20 600 36 2,900 1.74
Inconel 718 2.0 20 400 16 3,900 1.04

Drilling Power (Pc in kW) — Solid Carbide, κr=140°

Material D (mm) f (mm/rev) n (rpm) Q (cm³/min) kc Pc (kW)
Ck45 10 0.18 6,370 90.0 2,600 3.9
42CrMo4 12 0.16 4,240 76.8 2,900 3.7
316L 8 0.10 3,980 20.0 3,200 1.07
GJL-250 14 0.25 6,820 262 1,600 7.0
Aluminium 6082 10 0.30 19,100 450 820 6.15

5. Worked Examples

Example 1 — Turning 42CrMo4 at ap=2.5, f=0.25, Vc=180

  • Q = 2.5 × 0.25 × 180 = 112.5 cm³/min
  • h = f = 0.25 mm; kc = 2,350 × (1.1/0.25)0.13 = 2,350 × 1.20 = 2,820 N/mm²
  • Pc = 2,820 × 112.5 / 60,000 = 5.29 kW (net)
  • With η = 0.80: Pspindle = 5.29 / 0.80 = 6.6 kW
  • n = 1,000 × 180 / (π × 80) = 716 rpm; T = 9,550 × 5.29 / 716 = 70.5 Nm

Example 2 — Face milling Ck45 with a ø63 face mill, Z=5, ap=5, ae=50, Vc=200, fz=0.15

  • n = 1,000 × 200 / (π × 63) = 1,010 rpm
  • vf = 0.15 × 5 × 1,010 = 758 mm/min
  • Q = 5 × 50 × 758 / 1,000 = 189.5 cm³/min
  • Pc = 2,300 × 189.5 / 60,000 = 7.26 kW (net) → ~9.1 kW at spindle

Example 3 — Drilling GJL-250 with ø14 carbide drill, f=0.25, Vc=300

  • n = 1,000 × 300 / (π × 14) = 6,820 rpm
  • Q = (π × 14² / 4) × 0.25 × 6,820 / 1,000 = 262 cm³/min
  • Pc = 1,600 × 262 / 60,000 = 6.99 kW (net) → ~8.7 kW at spindle

6. Torque vs. Speed: Respecting the Spindle Limit Curve

CNC spindles deliver constant torque up to a corner speed (typically 1,000–3,000 rpm) and constant power above it. A cut that is fine at 6,000 rpm can stall the spindle at 1,200 rpm because torque demand rises as n drops. The rule of thumb:

  • Below the corner speed, check torque T = 9,550 × Pc / n against the rated torque.
  • Above the corner speed, check power Pspindle against the rated power.
  • For heavy roughing of steel at low rpm, torque is usually the binding constraint; for high-speed aluminium milling, power is.

7. Brand-Specific Cutting Data Reference

Catalogue data from the major toolmakers align closely with the kc model when Vc, fz and ap are converted back to Q. The table below summarizes recommended removal rates for a 15 kW (S6-40%) spindle under continuous cut, with carbide inserts.

Material Sandvik (GC4325 / CoroMill 490) Iscar (IC8250 / HELIDO) Seco (TP3501 / Turbo 12)
Steel P20-35 Vc 200, fz 0.15, ap 5 Vc 180, fz 0.16, ap 5 Vc 210, fz 0.14, ap 4.5
Stainless M20-30 Vc 130, fz 0.12, ap 3 Vc 120, fz 0.13, ap 3 Vc 140, fz 0.11, ap 3
Cast iron K20-30 Vc 300, fz 0.20, ap 6 Vc 280, fz 0.22, ap 6 Vc 320, fz 0.18, ap 5.5
Aluminium N Vc 800, fz 0.25, ap 8 Vc 900, fz 0.28, ap 8 Vc 850, fz 0.26, ap 8
Titanium S Vc 70, fz 0.10, ap 2 Vc 60, fz 0.12, ap 2 Vc 75, fz 0.09, ap 2

All three vendors converge on the same power envelope because the physics is material-driven; the differences are 5–15% and reflect coating, edge preparation, and insert geometry. Always derate by at least 20% for interrupted cuts and 15% for long overhangs.

8. Practical Guidelines

  • Stay below 80% of rated power for continuous cuts. The last 20% is your safety margin for worn tools, hard spots, and coolant drop-out.
  • Reduce ap, not f, when power is tight. Cutting force scales linearly with ap but feed also affects surface finish and chip control; prefer splitting a heavy pass into two lighter passes.
  • Use high-pressure coolant (70+ bar) for stainless, titanium, and superalloys. It can reduce effective kc by 5–10% and dramatically extend tool life at the same Vc.
  • Chip thinning in high-feed and circular milling means h is much smaller than fz; your effective kc goes up, not down. Increase fz proportionally to restore the target h and keep the cut economical.
  • Drill power spikes at entry and exit. The chisel edge of a twist drill can double the peak kc; use a spot drill or chamfer to reduce the entry shock.
  • Monitor spindle load meter. A sustained reading above 85% in steady state means the cut is too heavy; above 95% and an immediate pull-back is warranted.

9. Conclusion

Specific cutting force kc is the single number that connects workpiece material, chip cross-section, and machine capacity. By calculating Q from your depths and feeds, looking up kc1.1 for the material, and applying the Kienzle correction for chip thickness, you can predict spindle power and torque before the tool touches the part. The worked examples and the Sandvik/Iscar/Seco reference table give you the anchor points; the rule of staying under 80% of rated power gives you the margin. A 60-second power check before cycle start is the cheapest insurance in the workshop.

Shop Related Products at HOOGUU

Written by

WeChat QR Code

扫码添加微信

Scan to add WeChat

WhatsApp

Cart